FANUC系统铣床与加工中心工艺编程与操作实例.doc

H:精品资料建筑精品网原稿ok（删除公文）建筑精品网5未上传百度单元二 外轮廓零件加工课题一 平面加工图211 平面加工任务图参考程序: O0001; G90 G94 G21 G17; G91 G28 Z0; G90 G54 M03 S350; G00 X-52.0 Y-50.0; Z5.0 M08; G01 Z-8.0 F50; Y50.0 F52; G00 Z5.0; X-44.0 Y-50.0; G01 Z-4.0 F50; Y50.0 F52; G00 Z5.0; X10. Y50.0; G01 Z-6.0 F50; G02 X10.0 Y-50.0 R50.0 F52; G00 Z20.0 M09; G91 G28 Z0; M30; 课题二 外形轮廓加工图221 零件加工任务图参考程序: ( 1) 圆柱台加工程序0001; G90 G94 G40 G17 G21; G91 G28 Z0; G90 G54 M3 S350; G00 X62.0 Y0; Z5.0; G01 Z-4.0 F52; G41 D02 G01 X47.0 Y0 F52; G02 I-47.0 J0; G40 G01 X62.0 Y0; G41 D02 G01 X31.0 YO; G02 I-31.0 J0; G40 G01 X62.0 Y0; G41 D02 G01 X15.0 Y0; G02 I-15.0 J0; G40 G01 X62.0 Y0; G00 Z20.0; G91 G28 Z0; M30; ( 2) 外轮廓加工程序0002; G90 G94 G40 G17 G21; G91 G28 ZO; G90 G54 M03 S350; G00 X-62.0 Y52.0 M08; Z5.0; G01 Z-9.0 F52; G41 D02 G01 X-40.0 Y30.0 F52; G01 X-20.0 Y30.0; X30.0; G02 X40.0 Y20.0 R10.0; G01 Y-20.0; G02 X30.0 Y-30.0 R10.0; G01 X-30.0; G02 X-40.0 Y-20.0 R10.0; G01 Y10.0; G03 X-20.0 Y30.0 R20.0; G40 G01 X-62.0 Y52.0; G00 Z20.0 M09; G91 G28 Z0; M30; 粗加工时, 选用20的立铣刀, 刀具号为T02, 刀具半径补偿号为D02, 补偿值为10.2mm( 0.2mm是精加工余量) 。精加工时, 选用12的立铣刀, 刀具号为T03, 刀具半径补偿号为D03, 补偿值为6mm。单元三 内轮廓零件加工课题一 槽加工 图311 槽加工任务图参考程序: ( 1) 十字槽粗加工程序0001; G90 G40 G21 G17 G94; G91 G28 Z0; G90 G54 M3 S480; G00 X30.0 Y0; Z5.0 M08; G01 Z-4.0 F40; X-30.0 F60; Z-8.0 F40; X30.0 F60; G00 Z5.0; X0 Y25.0; G01 Z-4.0 F40; Y-25.0; Z-8.0 F40; Y25.0 F60; G00 Z5.0 M09; G91 G28 Z0; M30; ( 2) 十字槽精加工程序0002; ( 主程序) G90 G40 G21 G94 G17; G91 G28 Z0; G90 G54 M3 S800; G00 X0 Y0; Z5.0 M08; G01 Z0 F40; M98 P0003 L02; G90 G00 Z5.0 M09; G91 G28 Z0; M30; 0003; ( 子程序) G91 G01 Z-4.0 F40; G90 G41 D03 G01 X12.5 Y7.5 F50; G02 X7.5 Y12.5 R5.0; G01 Y25.0; G03 X-7.5 R7.5; G01 Y12.5; G02 X-12.5 Y7.5 R5.0; G01 X-30.0; G03 Y-7.5 R7.5; G01 X-12.5; G02 X-7.5 Y-12.5 R5.0; G01 Y-25.0 ; G03 X7.5 R7.5; G01 Y-12.5; G02 X12.5 Y-7.5 R5.0; G01 X30.0; G03 Y7.5 R7.5; G01 X12.5; G02 X7.5 Y12.5 R5.0; G40 G01 X0 Y0; M99; 课题二 型腔加工图331 型腔加工任务图参考程序: ( 1) 型腔内粗加工程序0001; ( 主程序) G90 G40 G21 G94 G17; G91 G28 Z0; G90 G54 M3 S480; G00 X0 Y0; Z5.0 M08; G01 Z0 F50; M98 P0002 L02; G00 Z20.0 M09; G91 G28 Z0; M30; 0002; ( 子程序) G91 G01 Z-4.0 F40; G90 G01 X7.0 Y0 F48; G03 I-7.0 J0; G01 X19.0 Y0; G03 I-19.0 J0; G01 X0 Y0 F100; M99; ( 2) 型腔内轮廓精加工程序0003; ( 主程序) G90 G40 G21 G94 G17; G91 G28 Z0; G90 G54 M3 S480; G00 X5.0 Y0; Z5.0 M08; G01 Z0 F80; M98 P0004 L02; G00 Z20.0 M09; G91 G28 Z0; M30; 0004; ( 子程序) G91 G01 Z-4.0 F80; G90 G41 D01 G01 X20.0 Y-15.0 F48; G03 X35.0 Y0 R15.0; G01 Y6.7157; G03 X28.3333 Y16.1438 R10.0; G02 X16.1438 Y28.3333 R20.0; G03 X6.7157 Y35.0 R10.0; G01 X-6.7157; G03 X-16.1438 Y28.3333 R10.0; GO2 X-28.3333 Y16.1438 R20.0; G03 X-35.0 Y6.7157 R10.0; G01 Y-6.7157; G03 X-28.3333 Y-16.1438 R10.0; G02 X-16.1438 Y-28.3333 R20.0; G03 X-6.7157 Y-35.0 R10.0; G01 X6.7157; G03 X16.1438 Y-28.3333 R10.0; G02 X28.3333 Y-16.1438 R20.0; G03 X35.0 Y-6.7157 R10.0; G01 Y0; G03 X20.0 Y15.0 R15.0; G40 G01 X5.0 Y0; M99; 单元四 孔加工课题一 钻孔、 攻丝加工图411 孔类零件加工任务图参考程序: 0001; G91 G28 Z0; M06 T1; G90 G17 G49 G21 G94; G54 M3 S1200; G00 X20.0 Y100.0 M08; G43 H01 G00 Z50.0; G99 G81 X-15.0 Y65.0 Z-4.0 R5.0 F80; G98 X-30.0; G00 X-120.0; Y15.0; G99 G81 X-85.0 Y15.0 Z-4.0 R5.0 F80; G98 X-70.0; G91 G28 Z0 M09; M06 T02; G90 G49 G54 M3 S550; G00 X20.0 Y100.0 M08; G43 H02 G00 Z50. ; G99 G73 X-15.0 Y65.0 Z-20.0 R5.0 Q2.0 F60; G98 X-30.0; G00 X-120.0; Y15.0; G99 G73 X-85.0 Y15.0 Z-20.0 R5.0 Q2.0 F60; G98 X-70.0; G91 G28 Z0 M09; M06 T03; G90 G49 G54 M3 S500; G00 X20.0 Y100.0 M08; G43 H03 G00 Z50. ; G98 G83 X-30.0 Y65.0 Z-21.0 R5.0 Q2.0 F60; G00 X-120.0; Y15.0; G98 G83 X-70.0 Y15.0 Z-21.0 R5.0 Q2.0 F60; G91 G28 Z0 M09; M06 T04; G90 G49 G54 M3 S450; G00 X20.0 Y100.0 M08; G43 H04 G00 Z50. ; G98 G81 X-15.0 Y65.0 Z-21.0 R5.0 F50; G00 X-120.0; Y15.0; G98 G81 X-85.0 Y15.0 Z-21.0 R5.0 F50; G91 G28 Z0 M09; M06 T05; G90 G49 G54 M3 S350; G00 X20.0 Y100.0 M08; G43 H05 G00 Z50.0; G99 G82 X-15.0 Y65.0 Z-6.0 R5.0 P F60; G98 X-30.0; G00 X-120.0; Y15.0; G99 G82 X-85.0 Y15.0 Z-6.0 R5.0 P F60; G98 X-70.0; G91 G28 Z0 M09; M06 T06; G90 G49 G54 M3 S50; G00 X20.0 Y100.0 M08; G43 H06 G00 Z50.0; G98 G85 X-30.0 Y65.0 Z-18.0 R5.0 F40; G00 X-120.0; Y15.0; G98 G85 X-70.0 Y15.0 Z-18.0 R5.0 F40; G91 G28 Z0 M09; M06 T07; G90 G49 G54 M3 S100; G00 X20.0 Y100.0 M08; G43 H07 G00 Z50.0; G98 G84 X-15.0 Y65.0 Z-19.0 R5.0 F175; G00 X-120.0; Y15.0; G98 G84 X-85.0 Y15.0 Z-19.0 R5.0 F175; G91 G28 Z0 M09; M30; 课题二 镗孔加工图421 零件加工任务图参考程序: 0001; G91 G28 Z0; M06 TO1; G90 G94 G49 G17 G40 G21; G54 M03 S400; G43 H01 G00 Z50.0 M08; X-46.0 Y55.0; Z5.0; G01 Z-4.0 F80; Y-55.0 F60; X46.0 F1000; Y55.0 F60; G41 D01 G01 X17.321 Y30.0 F60; X34.641 Y0; X17.321 Y-30.0; X-17.321; X-34.641 Y0; X-17.321 Y30.0 ; X-20.0; G40 G01 X65.0 Y55.0 F300; G91 G28 Z0 M09; M06 T03; G90 G54 G49 G40 M03 S1200; G43 H03 G00 Z50.0 M08; G98 G81 X0 Y0 Z-4.0 R5.0 F60; G91 G28 Z0 M09; M06 T04; G90 G54 G49 G40 M03 S500; G43 H04 G00 Z50.0 M08; G98 G81 X0 Y0 Z-20.0 R5.0 F60; G91 G28 Z0 M09; G28 X0 Y0; M06 T05; G90 G54 G49 G40 M03 S350; G43 H05 G00 Z50.0 M08; G98 G73 X0 Y0 Z-22.0 R5.0 Q2.0 F50; G91 G28 Z0 M09; G28 X0 Y0; M06 T06; G90 G54 G49 G40 M03 S250; G43 H06 G00 Z50.0 M08; G98 G73 X0 Y0 Z-25.0 R5.0 Q2.0 F45; G91 G28 Z0 M09; G28 X0 Y0; M06 T07; G90 G54 G49 G40 M03 S200; G43 H07 G00 Z50.0 M08; G98 G73 X0 Y0 Z-26.0 R5.0 Q2.0 F40; G91 G28 Z0 M09; M06 T02; G90 G54 G49 G40 M03 S800; G43 H02 G00 Z50.0 M08; X46.0 Y55.0; Z5.0; G01 Z-4.0 F80; G41 D02 G01 X17.321 Y30.0 F60; X34.641 Y0; X17.321 Y-30.0; X-17.321; X-34.641 Y0; X-17.321 Y30.0; X-20.0; G40 G01 X65.0 Y55.0 F300; G91 G28 Z0 M09; M06 T08; G90 G54 G49 G40 M03 S800; G43 H08 G00 Z60.0 M08; G98 G85 X0 Y0 Z-17.0 R5.0 F60; G91 G28 Z0 M09; M06 T09; G90 G54 G49 G40 M03 S1500; G43 H09 G00 Z60.0 M08; G98 G85 X0 Y0 Z-17.0 R5.0 F50; G91 G28 Z0 M09; G28 X0 Y0; M30; 单元五 综合课题加工课题一 镜像加工 图511 加工任务图参考程序: 0001; ( 主程序) G90 G40 G21 G17 G94; G50.1 X0 Y0G91 G28 Z0; G90 G54 M3 S680; M08M98 P0002G51.1 X0M98 P0002G50.1 X0M09M300002; ( 子程序) G00 X-58.0 Y-48.0; Z50.0; Z5.0; G01 Z-3.0 F50; G41 D01 G01 X-47.0 Y-45.0 F100; X-47.0 Y-20.0; X-37.0 Y-20.0; G03 X-27.0 Y-10.0 R10.0; G01 X-27.0 Y10.0; G03 X-37.0 Y20.0 R10.0; G01 X-47.0 Y20.0; X-47.0 Y42.5; X-28.0 Y42.5; G02 X-8.0 Y22.5 R20.0; G01 X-8.0 Y-20.0; X-30.5 Y-42.5; X-50.0 Y-42.5; G40 G01 X-58.0 Y-48.0; G00 Z50.0; M99; 课题二 极坐标加工图521 加工任务图参考程序: 0001; G54 G40; M08; G15; M03 S700; G00 X58.0 Y-10.0; Z50.0; Z5.0; G01 Z-5.0 F50; G41 D01 G16 G01 X36.0 Y-5.0 F100; G02 X24.0 Y-5.0 R6.; G03 X24.0 Y275.0 R-24.0; G02 X36.0 Y275.0 R6.0; G02 X36.0 Y-5.0 R-36.0; G40 G15 G01 X58.0 Y-10.0; G00 Z150.0; M09; M30; 课题三 旋转加工图531 加工任务图参考程序: 0001; G54 G40; G69; M03 S700; G68 X0 Y0 R30.0; G00 X0 Y0; Z50.0 M08; Z5.0; G01 Z-5.0 F50; G41 D01 G01 X25.0 Y10.0 F100; G03 X15.0 Y20.0 R10.0; G01 X-15.0; G03 X-25.0 Y10.0 R10.0; G01 Y-10.0; G03 X-15.0 Y-20.0 R10.0; G01 X15.0; G03 X25.0 Y-10.0 R10.0; G01 X25.0 Y10.0; G40 G01 X0 Y0; G00 Z150.0 M09; M30; 课题四 综合零件的加工 图541 加工任务图参考程序: ( 1) 正六边形加工程序0001; G90 G40 G21 G17 G94; G91 G28 Z0; G90 G54 M03 S400; G00 X0 Y55.0; Z5.0 M08; G01 Z-6. F60; G41 D01 G01 X0 Y29.0 F100; X10.97; G02 X19.63 Y24.0 R10.0; G01 X30.60 Y5.0; G02 Y-5.0 R10.0; G01 X19.63 Y-24.0; G02 X10.97 Y-29.0 R10.0; G01 X-10.97; G02 X-19.63 Y-24.0 R10.0; G01 X-30.60 Y-5.0; G02 Y5.0 R10.0; G01 X-19.63 Y24.0; G02 X-10.97 Y29.0 R10.0; G01 X0; G40 G01 X0 Y55.0; G00 Z50.0 M09; G91 G28 Z0; M30; ( 2) 斜六边形加工主程序0002; ( 主程序) G90 G40 G21 G17 G94 G69; G91 G28 Z0; G90 G68 X0 Y0 R10.0; M98 P0003; G69; G91 G28 Z0; M30; 0003; ( 子程序) G90 G54 M03 S400; G00 X0 Y40.0; Z5.0 M08; G01 Z-4. F60; G41 D01 G01 X0 Y25.0 F100; X10.97; G02 X16.17 Y22.0 R6.0; G01 X27.14 Y3.0; G02 Y-3.0 R6.0; G01 X16.17 Y-22.0; G02 X10.97 Y-25.0 R6.0; G01 X-10.97; G02 X-16.17 Y-22.0 R6.0; G01 X-27.14 Y-3.0; G02 Y3.0 R6.0; G01 X-16.17 Y22.0; G02 X-10.97 Y25.0 R6.0; G01 X0; G40 G01 X0 Y40.0; G00 Z50.0 M09; M99; ( 3) 凹槽加工程序0004; ( 主程序) G90 G40 G21 G17 G94; G54 M03 S680; GO0 X60 Y-50; Z5.0 M08; M98 P0005; G51.1 X0 Y0 ; M98 P0005; G50.1 X0 Y0 ; G0 Z100.0 M09; M300005; ( 子程序) G00 X56.0 Y-46.0; G01 Z-8.0 F50; G41 D04 G01 X52.34 Y-33.55 F ; X34.88 Y-19.58; G3 X26.76 Y-29.73 R6.5; G1 X41.94 Y-41.87; G40 G01 X56.0 Y-46.0; G00 Z5.0; M99; ( 4) 孔加工程序0006; G91 G28 Z0; M06 T05; G90 G40 G21 G17 G94 G15; G54 M03 S1500; GO0 X0 Y0; G43 H05 G00 Z20.0; G16 G00 X40.0 Y40.0; G99 G81 Z-9.0 R5.0 F60; G00 X40.0 Y210.0; G98 G81 Z-9.0 R5.0 F60; G15; G91 G28 Z0; M06 T06; G90 G15 G54 M3 S500; GO0 X0 Y0; G43 H06 G00 Z20.0; G16 G00 X40.0 Y40.0; G99 G81 Z-20.0 R5.0 F60; G00 X40.0 Y210.0; G98 G81 Z-20.0 R5.0 F60; G15; G91 G28 Z0; M06 T07; G90 G15 G54 M03 S450; GO0 X0 Y0; G43 H07 G00 Z20.0; G16 G00 X40.0 Y40.0; G99 G81 Z-20.0 R5.0 F50; G00 X40.0 Y210.0; G98 G81 Z-20.0 R5.0 F50; G15; G91 G28 Z0; M06 T08; G90 G15 G54 M03 S500; GO0 X0 Y0; G43 H08 G00 Z20; G16 G00 X40.0 Y40.0; G99 G82 Z-10.0 R5.0 P F60; G00 X40.0 Y210.0; G99 G82 Z-10.0 R5.0 P F60; G15; G91 G28 Z0; M06 T09; G90 G15 G54 M03 S50; GO0 X0 Y0; G43 H09 G00 Z20.0; G16 G00 X40.0 Y40.0; G99 G85 Z-18.0 R5.0 F40; G00 X40.0 Y210.0 G98 G85 Z-18.0 R5.0 F40; G15; G91 G28 Z0; M30; 数控编程实例1根据图样要求、 毛坯及前道工序加工情况, 确定工艺方案及加工路线1) 以已加工过的底面为定位基准, 用通用台虎钳夹紧工件前后两侧面, 台虎钳固定于铣床工作台上。2) 工步顺序 铣刀先走两个圆轨迹, 再用左刀具半径补偿加工5050四角倒圆的正方形。 每次切深为2, 分二次加工完。2选择机床设备根据零件图样要求, 选用经济型数控铣床即可达到要求。故选用XKN7125型数控立式铣床。3选择刀具现采用10的平底立铣刀, 定义为T01, 并把该刀具的直径输入刀具参数表中。4确定切削用量切削用量的具体数值应根据该机床性能、 相关的手册并结合实际经验确定, 详见加工程序。5确定工件坐标系和对刀点在XOY平面内确定以工件中心为工件原点, Z方向以工件表面为工件原点, 建立工件坐标系, 如图2-23所示。采用手动对刀方法( 操作与前面介绍的数控铣床对刀方法相同) 把点O作为对刀点。6编写程序按该机床规定的指令代码和程序段格式, 把加工零件的全部工艺过程编写成程序清单。考虑到加工图示的槽, 深为4, 每次切深为2, 分二次加工完, 则为编程方便, 同时减少指令条数, 可采用子程序。该工件的加工程序如下( 该程序用于XKN7125铣床) : N0010 G00 Z2 S800 T1 M03N0020 X15 Y0 M08N0030 G20 N01 P1.-2 ; 调一次子程序, 槽深为2N0040 G20 N01 P1.-4 ; 再调一次子程序, 槽深为4N0050 G01 Z2 M09N0060 G00 X0 Y0 Z150N0070 M02 ; 主程序结束N0010 G22 N01 ; 子程序开始N0020 G01 ZP1 F80N0030 G03 X15 Y0 I-15 J0N0040 G01 X20N0050 G03 X20 YO I-20 J0N0060 G41 G01 X25 Y15 ; 左刀补铣四角倒圆的正方形N0070 G03 X15 Y25 I-10 J0N0080 G01 X-15N0090 G03 X-25 Y15 I0 J-10N0100 G01 Y-15N0110 G03 X-15 Y-25 I10 J0N0120 G01 X15N0130 G03 X25 Y-15 I0 J10N0140 G01 Y0N0150 G40 G01 X15 Y0 ; 左刀补取消N0160 G24 ; 主程序结束1根据图样要求、 毛坯及前道工序加工情况, 确定工艺方案及加工路线1) 以底面为定位基准, 两侧用压板压紧, 固定于铣床工作台上2) 工步顺序 钻孔20。 按OABCDEFG线路铣削轮廓。2选择机床设备根据零件图样要求, 选用经济型数控铣床即可达到要求。故选用华中型( ZJK7532A型) 数控钻铣床。3选择刀具现采用20的钻头, 定义为T02,5的平底立铣刀, 定义为T01, 并把该刀具的直径输入刀具参数表中。由于华中型数控钻铣床没有自动换刀功能, 按照零件加工要求, 只能手动换刀。4确定切削用量切削用量的具体数值应根据该机床性能、 相关的手册并结合实际经验确定, 详见加工程序。5确定工件坐标系和对刀点在XOY平面内确定以0点为工件原点, Z方向以工件表面为工件原点, 建立工件坐标系, 如图3-24所示。采用手动对刀方法把0点作为对刀点。6编写程序( 用于华中I型铣床) 按该机床规定的指令代码和程序段格式, 把加工零件的全部工艺过程编写成程序清单。该工件的加工程序如下: 1) 加工20孔程序(手工安装好20钻头)%1337 N0010 G92 X5 Y5 Z5 ; 设置对刀点N0020 G91 ; 相对坐标编程N0030 G17 G00 X40 Y30 ; 在XOY平面内加工N0040 G98 G81 X40 Y30 Z-5 R15 F150 ; 钻孔循环N0050 G00 X5 Y5 Z50N0060 M05N0070 M022) 铣轮廓程序(手工安装好5立铣刀,不考虑刀具长度补偿)%1338 N0010 G92 X5 Y5 Z50N0020 G90 G41 G00 X-20 Y-10 Z-5 D01N0030 G01 X5 Y-10 F150N0040 G01 Y35 F150N0050 G91N0060 G01 X10 Y10 F150 N0070 G01 X11.8 Y0N0080 G02 X30.5 Y-5 R20N0090 G03 X17.3 Y-10 R20N0100 G01 X10.4 Y0N0110 G03 X0 Y-25N0120 G01 X-90 Y0N0130 G90 G00 X5 Y5 Z10N0140 G40N0150 M05N0160 M30 1根据图样要求、 毛坯及前道工序加工情况, 确定工艺方案及加工路线1) 以底面为主要定位基准, 两侧用压板压紧, 固定于铣床工作台上。2) 加工路线Y方向以行距小于球头铣刀逐步行切形成椭球形成。2选择机床设备根据零件图样要求, 选用经济型数控铣床即可达到要求。故选用华中型( ZJK7532A型) 数控钻铣床。3选择刀具球头铣刀大小f6mm。4确定切削用量切削用量的具体数值应根据该机床性能、 相关的手册并结合实际经验确定, 详见加工程序。5确定工件坐标系和对刀点在XOY平面内确定以工件中心为工件原点, Z方向以工件表面为工件原点, 建立工件坐标系, 如图2-25所示。采用手动对刀方法把0点作为对刀点。6编写程序( 用于华中I型铣床) 按该机床规定的指令代码和程序段格式, 把加工零件的全部工艺过程编写成程序清单。该工件的加工程序如下: %8005( 用行切法加工椭园台块, X, Y按行距增量进给) #10=100; 毛坯X方向长度#11=70; 毛坯Y方向长度#12=50; 椭圆长轴#13=20; 椭圆短轴#14=10; 椭园台高度#15=2; 行距步长G92 X0 Y0 Z#13+20G90G00 X#10/2 Y#11/2 M03G01 Z0X-#10/2 Y#11/2G17G01 X-#10/2 Y-#11/2X#10/2Y#11/2#0=#10/2#1=-#0#2=#13-#14#5=#12*SQRT1-#2*#2/#13/#13G01 Z#14WHILE #0 GE #1IF ABS#0 LT #5#3=#13*SQRT1-#0*#0/#12*#12IF #3 GT #2#4=SQRT#3*#3-#2*#2G01 Y#4 F400G19 G03 Y-#4 J-#4 K-#2ENDIFENDIFG01 Y-#11/2 F400#0=#0-#15G01 X#0IF ABS#0 LT #5#3=#13*SQRT1-#0*#0/#12*#12IF #3 GT #2#4=SQRT#3*#3-#2*#2G01 Y-#4 F400G19 G02 Y#4 J#4 K-#2ENDIFENDIFG01 Y#11/2 F1500#0=#0-#15G01 X#0ENDWG00 Z#13+20 M05G00 X0 Y0M02具体加工工艺和装夹方法和其余各题一样, 这里略。程序如下: ( 用于华中I型铣床) %1978 #10=100 ;底平面EF的长度, 可根据加工要求任定#0=#10/2 ; 起刀点的横座标( 动点) #100=20 ; C点的横座标#1=20 ; C点和G点的纵向距离#11=70; FG的长度#20=-#10/2 ; E点的横座标#15=3; 步长#4=16 ; 棱台高#5=3; 棱台底面相对于Z=0平面的高度#6=20; C点的纵座标G92 X0 Y0 Z#4+#5+2 ; MDI对刀点Z向距毛坯上表面距离G00 X0 Y0 G00 Z#4+10 M03G01 X#0 Y#11/2 Z#5 ; 到G点WHILE #0 GE #20 ; 铣棱台所在的凹槽IF ABS#0 LE #100G01 Y#1 F100X0 Y0 Z#4+#5X#0 Y-#1 Z#5Y-#11/2ENDIF G01 Y-#11/2 F100#0=#0-#15G01 X#0IF ABS#0 le #100G01 Y-#1X0 Y0 Z#4+#5X#0 Y#1 Z#5Y#11/2ENDIFG01 Y#11/2#0=#0-#15G01 X#0ENDWG01 Z#4+20X0 Y0X#1 Y#1 Z#5WHILE ABS#6 LE #1 ; 铣棱台斜面#6=#6-#15G01 Y#6X0 Y0 Z#4+#5X-#1 Y-#6 Z#5G01 Y-#6+#15X0 Y0 Z#4+#5X#1 Y#6 Z#5ENDW